Crop View in Inventor 2011
Crop operations provide the means of clipping drawing views with a defined boundary. A Crop operation is performed on existing views except of the following view types:
- Views containing a view break (broken view)
- Views with overlays
- Suppressed views
- Views that are already cropped
On the cropped views, you can perform following view operations:
- Break Out view
- Detail view
- Slice operation
Crop operations can be performed on a view with circular or rectangular shapes or a predefined view sketch.
Cropped views are created by altering established drawing views.
- Part view
- Assembly view
- Projected view
- Isometric view
- Section view
- Slice operation
Crop operations support all types of drawing annotations. Annotations can be anchored to endpoints of cropped geometry including edges produced from the crop edges, if they are displayed.
Crop affects existing sheet dimensions. When annotation anchors are lost, annotations become sick.
Centerlines and center marks
Crop affects existing centerlines and center marks of all types. When anchors are lost, annotations become sick.
When a crop operation is executed, first the type of boundary (circular or rectangular) must be selected. A circular boundary can be specified by a center point of circle and a point on the circle. A rectangular boundary can be specified by two points which define the diagonal of the rectangle.
- On the ribbon, click Place Views tabModify panel Crop.
- Select the view to crop.
- Right click to select either circular or rectangular boundary type.
- To set default boundary type select Crop Settings to launch the crop settings dialog. Within the Crop Settings dialog box, select default boundary type. Check to display Crop boundary. Selected crop type is set as the default type.
- According to selected boundary type, specify the center for circular boundary or specify two corners for a rectangular boundary.
An existing view sketch that qualifies as a crop sketch can be used to crop a view. To qualify as a crop sketch, the sketch must contain a single non self-intersecting loop. The sketch must be associated with the view.
- On the ribbon, click Place Views tab Modify panel Crop.
- Select the associated sketch.
- Define the boundaries for the crop operation. Specify two corners for rectangular boundary, or a center point for circular boundary type. The boundary for the crop in the sketch is not limited to rectangles and circles. Use any sketch geometry as long as the geometry forms a single non self-intersecting loop.
Model geometry can be projected into sketches used for cropping. If the model geometry changes, the crop sketch may become invalid for cropping.
Crop sketches can be edited just like any other view sketch. To edit a crop sketch, open the corresponding crop node in the browser, select the sketch, right-click and then select Edit. When you leave existing sketch environment the sketch is validated for cropping.
If the sketch is still valid for cropping, the view updates to accommodate the changes to the sketch. If the sketch is no longer valid for cropping, then a dialog box is displayed indicating the reason the sketch is invalid. Select “Cancel” to cancel the edit and continue in the sketch environment. Select “Continue” to exit the sketch environment. Exiting the sketch environment with an invalid sketch marks the crop node with a warning icon and the view is not cropped.
Boundary types can be set for crop operations. On the ribbon, click Place Views tab Modify panel Crop, select a view to be cropped, and right-click to display the context menu. Select the crop boundary type directly in the context menu (Rectangular or Circular) or click Crop Setting to display Crop Settings dialog box.
The boundary type selected directly in the context menu is applied to a particular crop operation. The boundary type selected in the Crop Settings dialog box is set as a default type for the next crop operations.